SolidCAM HAAS Lathe Startup Guide

==SOLIDCAM HAAS LATHE STARTUP GUIDE==
This tutorial details the process of producing a CAM code for the HAAS Lathe using SolidCAM by walking through the process for an example part. 
===Example Lathe Part SolidCAM Tutorial===
#Design or import a part in SolidWorks.
#:thumb|500px|none|Example Part
#Save post processor files on the C: drive if they are not already present. 
#*Post processor files are located on the shared drive at: Z:\Engineering\SeniorDesign\- Group Folders\IEW\Machine Shop\SolidCAM Post Processor\Lathe HAAS
#*Copy Postprocessor files to the local c drive at: C:\Users\Public\Documents\SolidCAM\SolidCAM2016\Gpptool
#*Once completed, close both SolidCAM and SolidWorks and reopen to reinitialize.
#Open New Mill Turn part under the SolidCAM Part tab in SolidWorks
#:thumb|500px|none|Opening a SolidCAM Turn Part
#Set up part (Suggested Settings)
#:thumb|500px|none|Turn Part Option Settings
#Fill in Part Data
#*Under CNC-Machine Select: gTurn_Haas_2xUofIdaho
#*Select: CoordSys
#*Define an origin: click Select Face, then select Revolute Face. 
#:(The origin should be at the end of the part or a natural location to zero the tool. Z is in the direction of rotation)
#*Click Green Checkmark
#:(The remaining fields should auto fill)
#:thumb|500px|none|Part Origin
#:thumb|500px|none|Turn Part Data Menu, All Data Entered
# Create a Tool
##Double Click Tool List in design tree
##Select New Lathe Tool 
#:thumb|500px|none|New Lathe Tool Button
##Select the tool you plan to use for the current operation.
##Change the geometry of the Tool Insert as shown below.
#:thumb|500px|none|Tool Insert Geometry Settings
##Adjust the Shank Settings as shown below. 
#:thumb|500px|none|Shank Parameter Settings
##Set Tool Parameters according to the material to be cut. 
##*(In this case carbide cutting 0.5” brass is selected) 
##*The HAAS lathe spindle's maximum speed is 1800 RPM. 
##* This website provides a feed and turning speed calculator: 
#:thumb|500px|none|Tool Parameter Settings
##Select the Mounting >> button in the upper right hand corner. In this menu use the Z+,Z-,X+,and X- buttons to orientate the tool such that it is positioned as it would be on the actual HAAS lathe's tool holder. 
##*The tools location in space is irrelevant. Pay attention to the axis orientation of the part. 
##:*The X-Axis should point towards the operator when standing in front of the machine. 
##:When the tool is properly oriented, save and exit the mounting dialog.
#:thumb|500px|none|Tool Coordinate System
#:thumb|500px|none|HAAS Lathe Coordinate System
# Make a Turning Operation
##Under Turning select the Turning Operation. 
##Select the solid features to turn then click New Geometry in the Geometry Tab.
#:thumb|500px|none|Geometry Tab Settings
##Select the Start and End faces then the green checkmark to select a Chain.
#:thumb|500px|none|Tool Path Chain
##*The Lathe will sweep the tool from the starting face to the ending face as is cuts the part.
##*Care should be take to ensure that the tool, both the insert and holder, will not interfere with the part as it is swept along the part.
##Select the tool we previously defined.
##In the Levels menu, set the safety distance.
##* 0.1” is acceptable.
##In the Technology menu, select the operation as desired.
##* Technology refers to the machining styles / technique used. For example, if we were milling technology could refer to cutting a pocket using a spiral pattern or a level drilling followed by finishing sweeps.
##Under the Link menu, set the Lead In – Lead Out and the Approach and Retract settings.
##*(Default settings are usually fine)
##* Lean In and Lead Out refer to the x axis tool approach and retraction method.
##* Approach and Retract refer to the z axis approach and retraction method of the tool.